動作確認結果

実行可能かの検証（〇：実行可能、罰：エラー等で実行不可）

	OF10 interFoam	OF11 incompressibleVoF	OpenFOAM2306 interFoam	OpenFOAM2306 interIsoFoam
OpenFOAM10	〇	×	×	×
OpenFOAM11	〇	〇	×	×
OpenFOAM2306	×	×	〇	〇

まとめ

OpenFOAM11がOpenFOAM10のチュートリアルを実行できるのみで他のバージョン間でのチュートリアルの互換性はない。
OpenFOAM10はOpenFOAM2306とファイル名が変わったものもあり、書き換えが必要。
OpenFOAM11のチュートリアルはsolver名の指定が変わったことで他のバージョンでは実行できない。
OpenFOAM10と11はcontrolDictのadjustableRunTimeがadjustableに変わったことでOpenCFD側のチュートリアルが実行できない。

実行ログの確認

OpenFOAM10でOpenFOAM10のinterFoam-dambreakを実施

ソルバーとチュートリアルが一緒のため、実行可能。

Running blockMesh on /mnt/c/Users/hamma/Documents/97thOpenCAE/OF10/damBreak_interFoam_OF10/damBreak
Running setFields on /mnt/c/Users/hamma/Documents/97thOpenCAE/OF10/damBreak_interFoam_OF10/damBreak
Running interFoam on /mnt/c/Users/hamma/Documents/97thOpenCAE/OF10/damBreak_interFoam_OF10/damBreak
Cloning damBreakFine case from damBreak
Running blockMesh on /mnt/c/Users/hamma/Documents/97thOpenCAE/OF10/damBreak_interFoam_OF10/damBreakFine
Running setFields on /mnt/c/Users/hamma/Documents/97thOpenCAE/OF10/damBreak_interFoam_OF10/damBreakFine
Running decomposePar on /mnt/c/Users/hamma/Documents/97thOpenCAE/OF10/damBreak_interFoam_OF10/damBreakFine
Running interFoam in parallel on /mnt/c/Users/hamma/Documents/97thOpenCAE/OF10/damBreak_interFoam_OF10/damBreakFine using 4 processes
Running reconstructPar on /mnt/c/Users/hamma/Documents/97thOpenCAE/OF10/damBreak_interFoam_OF10/damBreakFine

OpenFOAM10でOpenFOAM11のincompressibleVoF-dambreakを実行

エコー自体は正常に見える。

Running blockMesh on /mnt/c/Users/hamma/Documents/97thOpenCAE/OF10/damBreak_incompressibleVoF_OF11/damBreak
Running setFields on /mnt/c/Users/hamma/Documents/97thOpenCAE/OF10/damBreak_incompressibleVoF_OF11/damBreak
Running foamRun on /mnt/c/Users/hamma/Documents/97thOpenCAE/OF10/damBreak_incompressibleVoF_OF11/damBreak
Cloning damBreakFine case from damBreak
Running blockMesh on /mnt/c/Users/hamma/Documents/97thOpenCAE/OF10/damBreak_incompressibleVoF_OF11/damBreakFine
Running setFields on /mnt/c/Users/hamma/Documents/97thOpenCAE/OF10/damBreak_incompressibleVoF_OF11/damBreakFine
Running decomposePar on /mnt/c/Users/hamma/Documents/97thOpenCAE/OF10/damBreak_incompressibleVoF_OF11/damBreakFine
Running foamRun in parallel on /mnt/c/Users/hamma/Documents/97thOpenCAE/OF10/damBreak_incompressibleVoF_OF11/damBreakFine using 4 processes
Running reconstructPar on /mnt/c/Users/hamma/Documents/97thOpenCAE/OF10/damBreak_incompressibleVoF_OF11/damBreakFine

foamRunがないためエラー

./Allrun: 93: foamRun: not found

OpenFOAM10でOpenFOAM2306のinterFoam-dambreakを実行

restore0DirとnotTestのコマンドがないというエラー。

./Allrun: 6: restore0Dir: not found
Running blockMesh on /mnt/c/Users/hamma/Documents/97thOpenCAE/OF10/damBreak_interFoam_OF2306/damBreak
Running setFields on /mnt/c/Users/hamma/Documents/97thOpenCAE/OF10/damBreak_interFoam_OF2306/damBreak
Running interFoam on /mnt/c/Users/hamma/Documents/97thOpenCAE/OF10/damBreak_interFoam_OF2306/damBreak
./Allrun: 29: notTest: not found

log.blockMeshでControlDictのadjustableRunTimeがadjustableに名称変更したことによるエラー。

Create time



--> FOAM FATAL IO ERROR: 
adjustable is not in enumeration: 
5
(
adjustableRunTime
clockTime
cpuTime
runTime
timeStep
)


file: /mnt/c/Users/hamma/Documents/97thOpenCAE/OF10/damBreak_interFoam_OF2306/damBreak/system/controlDict/writeControl at line 29.

    From function Enum Foam::NamedEnum<Enum, nEnum>::read(Foam::Istream&) const [with Enum = Foam::Time::writeControl; unsigned int nEnum = 5]
    in file lnInclude/NamedEnum.C at line 69.

FOAM exiting

setFieldとinterFoamも同様にエラー

OpenFOAM10でOpenFOAM2306のinterIsoFoam-dambreakを実行

restore0DirとnotTestのコマンドがないというエラー。interIsoFoamはもちろん存在しないためエラー。

./Allrun: 6: restore0Dir: not found
Running blockMesh on /mnt/c/Users/hamma/Documents/97thOpenCAE/OF10/damBreak_interIsoFoam_OF2306
Running setFields on /mnt/c/Users/hamma/Documents/97thOpenCAE/OF10/damBreak_interIsoFoam_OF2306
Running interIsoFoam on /mnt/c/Users/hamma/Documents/97thOpenCAE/OF10/damBreak_interIsoFoam_OF2306
invalid option '-vtp'

Usage: foamSequenceVTKFiles [OPTIONS] ...
options:
  -case | -c <dir>    specify case directory (default = local dir)
  -dir  | -d <dir>    post-processing directory <dir> (default = postProcessing)
  -help | -h          print the usage
  -out  | -o <dir>    output links directory <dir> (default = sequencedVTK)

Creates symbolic links to all VTK files in a post-processing directory
Links form a sequence like 'patch.0000.vtk', 'patch.0001.vtk', etc.

If files of the same name exist in different sub-directories of the main
directory, e.g. 'inletPatch/0/patch.vtk' and 'outletPatch/0/patch.vtk', a
further index is appended to the name in the links, e.g. 'patch0.0000.vtk' and
'patch1.0000.vtk'

Paraview recognises the link names as a sequence which can be opened and played.
The sequence of links to images can be used to create a video from the images.
- Default directory name for VTK files is 'postProcessing'

blockMeshとsetFieldsはadjustableのエラーが発生。

Create time



--> FOAM FATAL IO ERROR: 
adjustable is not in enumeration: 
5
(
adjustableRunTime
clockTime
cpuTime
runTime
timeStep
)


file: /mnt/c/Users/hamma/Documents/97thOpenCAE/OF10/damBreak_interIsoFoam_OF2306/system/controlDict/writeControl at line 30.

    From function Enum Foam::NamedEnum<Enum, nEnum>::read(Foam::Istream&) const [with Enum = Foam::Time::writeControl; unsigned int nEnum = 5]
    in file lnInclude/NamedEnum.C at line 69.

FOAM exiting

OpenFOAM11でOpenFOAM10のinterFoam-dambreakを実施

実行可能であることを確認した。

Running blockMesh on /mnt/c/Users/hamma/Documents/97thOpenCAE/OF11/damBreak_interFoam_OF10/damBreak
Running setFields on /mnt/c/Users/hamma/Documents/97thOpenCAE/OF11/damBreak_interFoam_OF10/damBreak
Running interFoam on /mnt/c/Users/hamma/Documents/97thOpenCAE/OF11/damBreak_interFoam_OF10/damBreak
Cloning damBreakFine case from damBreak
Running blockMesh on /mnt/c/Users/hamma/Documents/97thOpenCAE/OF11/damBreak_interFoam_OF10/damBreakFine
Running setFields on /mnt/c/Users/hamma/Documents/97thOpenCAE/OF11/damBreak_interFoam_OF10/damBreakFine
Running decomposePar on /mnt/c/Users/hamma/Documents/97thOpenCAE/OF11/damBreak_interFoam_OF10/damBreakFine
Running interFoam in parallel on /mnt/c/Users/hamma/Documents/97thOpenCAE/OF11/damBreak_interFoam_OF10/damBreakFine using 4 processes
Running reconstructPar on /mnt/c/Users/hamma/Documents/97thOpenCAE/OF11/damBreak_interFoam_OF10/damBreakFine

OpenFOAM11でOpenFOAM11のincompressibleVoF-dambreakを実行

バージョン一致のため実行可能。

Running blockMesh on /mnt/c/Users/hamma/Documents/97thOpenCAE/OF11/damBreak_incompressibleVoF_OF11/damBreak
Running setFields on /mnt/c/Users/hamma/Documents/97thOpenCAE/OF11/damBreak_incompressibleVoF_OF11/damBreak
Running foamRun on /mnt/c/Users/hamma/Documents/97thOpenCAE/OF11/damBreak_incompressibleVoF_OF11/damBreak
Cloning damBreakFine case from damBreak
Running blockMesh on /mnt/c/Users/hamma/Documents/97thOpenCAE/OF11/damBreak_incompressibleVoF_OF11/damBreakFine
Running setFields on /mnt/c/Users/hamma/Documents/97thOpenCAE/OF11/damBreak_incompressibleVoF_OF11/damBreakFine
Running decomposePar on /mnt/c/Users/hamma/Documents/97thOpenCAE/OF11/damBreak_incompressibleVoF_OF11/damBreakFine
Running foamRun in parallel on /mnt/c/Users/hamma/Documents/97thOpenCAE/OF11/damBreak_incompressibleVoF_OF11/damBreakFine using 4 processes
Running reconstructPar on /mnt/c/Users/hamma/Documents/97thOpenCAE/OF11/damBreak_incompressibleVoF_OF11/damBreakFine

OpenFOAM11でOpenFOAM2306のinterFoam-dambreakを実行

restore0DirとnotTestのコマンドがないというエラー。

./Allrun: 6: restore0Dir: not found
Running blockMesh on /mnt/c/Users/hamma/Documents/97thOpenCAE/OF11/damBreak_interFoam_OF2306/damBreak
Running setFields on /mnt/c/Users/hamma/Documents/97thOpenCAE/OF11/damBreak_interFoam_OF2306/damBreak
Running interFoam on /mnt/c/Users/hamma/Documents/97thOpenCAE/OF11/damBreak_interFoam_OF2306/damBreak
./Allrun: 29: notTest: not found

log.blockMeshでControlDictのadjustableRunTimeがadjustableに名称変更したことによるエラー。

Create time



--> FOAM FATAL IO ERROR: 
adjustable is not in enumeration: 
5
(
adjustableRunTime
clockTime
cpuTime
runTime
timeStep
)


file: /mnt/c/Users/hamma/Documents/97thOpenCAE/OF11/damBreak_interFoam_OF2306/damBreak/system/controlDict/writeControl at line 29.

    From function Enum Foam::NamedEnum<Enum, nEnum>::read(Foam::Istream&) const [with Enum = Foam::Time::writeControl; unsigned int nEnum = 5]
    in file lnInclude/NamedEnum.C at line 69.

FOAM exiting

setFields、interFoamも同様。

OpenFOAM11でOpenFOAM2306のinterIsoFoam-dambreakを実行

restore0DirとnotTestのコマンドがないというエラー。interIsoFoamももちろんないのでエラー。

./Allrun: 6: restore0Dir: not found
Running blockMesh on /mnt/c/Users/hamma/Documents/97thOpenCAE/OF11/damBreak_interIsoFoam_OF2306
Running setFields on /mnt/c/Users/hamma/Documents/97thOpenCAE/OF11/damBreak_interIsoFoam_OF2306
Running interIsoFoam on /mnt/c/Users/hamma/Documents/97thOpenCAE/OF11/damBreak_interIsoFoam_OF2306
invalid option '-vtp'

Usage: foamSequenceVTKFiles [OPTIONS] ...
options:
  -case | -c <dir>    specify case directory (default = local dir)
  -dir  | -d <dir>    post-processing directory <dir> (default = postProcessing)
  -help | -h          print the usage
  -out  | -o <dir>    output links directory <dir> (default = sequencedVTK)

Creates symbolic links to all VTK files in a post-processing directory
Links form a sequence like 'patch.0000.vtk', 'patch.0001.vtk', etc.

If files of the same name exist in different sub-directories of the main
directory, e.g. 'inletPatch/0/patch.vtk' and 'outletPatch/0/patch.vtk', a
further index is appended to the name in the links, e.g. 'patch0.0000.vtk' and
'patch1.0000.vtk'

Paraview recognises the link names as a sequence which can be opened and played.
The sequence of links to images can be used to create a video from the images.
- Default directory name for VTK files is 'postProcessing'

blockMeshとsetFieldsはadjustableのエラーが発生。

Create time



--> FOAM FATAL IO ERROR: 
adjustable is not in enumeration: 
5
(
adjustableRunTime
clockTime
cpuTime
runTime
timeStep
)


file: /mnt/c/Users/hamma/Documents/97thOpenCAE/OF11/damBreak_interFoam_OF2306/damBreak/system/controlDict/writeControl at line 29.

    From function Enum Foam::NamedEnum<Enum, nEnum>::read(Foam::Istream&) const [with Enum = Foam::Time::writeControl; unsigned int nEnum = 5]
    in file lnInclude/NamedEnum.C at line 69.

FOAM exiting

OpenFOAM2306でOpenFOAM10のinterFoam-dambreakを実施

エコーは正常。

Running blockMesh on /mnt/c/Users/hamma/Documents/97thOpenCAE/OF2306/damBreak_interFoam_OF10/damBreak
Running setFields on /mnt/c/Users/hamma/Documents/97thOpenCAE/OF2306/damBreak_interFoam_OF10/damBreak
Running interFoam on /mnt/c/Users/hamma/Documents/97thOpenCAE/OF2306/damBreak_interFoam_OF10/damBreak
Cloning damBreakFine case from damBreak
Running blockMesh on /mnt/c/Users/hamma/Documents/97thOpenCAE/OF2306/damBreak_interFoam_OF10/damBreakFine
Running setFields on /mnt/c/Users/hamma/Documents/97thOpenCAE/OF2306/damBreak_interFoam_OF10/damBreakFine
Running decomposePar on /mnt/c/Users/hamma/Documents/97thOpenCAE/OF2306/damBreak_interFoam_OF10/damBreakFine
Running interFoam (4 processes) on /mnt/c/Users/hamma/Documents/97thOpenCAE/OF2306/damBreak_interFoam_OF10/damBreakFine
Running reconstructPar on /mnt/c/Users/hamma/Documents/97thOpenCAE/OF2306/damBreak_interFoam_OF10/damBreakFine

interFoamでファイルが見つからないエラー。transportPropertiesがmomentumTransportに変わったことによるもの。

Create time

Create mesh for time = 0


PIMPLE: Operating solver in PISO mode

Reading field p_rgh

Reading field U

Reading/calculating face flux field phi

Reading transportProperties



--> FOAM FATAL ERROR: (openfoam-2306)
cannot find file "/mnt/c/Users/hamma/Documents/97thOpenCAE/OF2306/damBreak_interFoam_OF10/damBreak/constant/transportProperties"

    From virtual Foam::autoPtr<Foam::ISstream> Foam::fileOperations::uncollatedFileOperation::readStream(Foam::regIOobject&, const Foam::fileName&, const Foam::word&, bool) const
    in file global/fileOperations/uncollatedFileOperation/uncollatedFileOperation.C at line 627.

FOAM exiting

OpenFOAM2306でOpenFOAM11のincompressibleVoF-dambreakを実行